INCON-M84/M86/M86R Manual

3.2.5.7.1 Rectangular Dowel Machining

Format: G70.02(G02/G03)(P_)X_Y_Z_U_V_W_A_B_(C_ J_K_)Q_(L_/R_ D_) I_(E_F_)

"G70.02 Rectangular Dowel (Metric Mode)" Dialog Box

• Orientation (G): The cutting orientation can be clockwise (CW, G02) or counterclockwise (CCW , G03).
• Step In Axis (P): can be Not Defined, + 1st Axis, + 2nd Axis, - 1st Axis, and - 2nd Axis, which will be shown as P0~P4 command in the program. The orientation of 1st axis and 2nd axis are depends on the working plane (G17/G18/G19).

• Center X/Y/Z: center of dowel machining. It can be absolute positions or incremental values.
• Length/Depth of X/Y/Z axis: In G17 mode (X-Y plane), Length/Depth X and Y (U and V value) define length and width of the rectangular dowel. Length/Depth Z (W value) defines depth of the dowel and the value is negative.
• Axis1/Axis2 Peri Length (A and B value): define outer length and width of the rectangular dowel. Value A and B must be greater than value U and V.
• Clearance (C value): the safe starting height for machining.
• Fine Feed Width (J value) and Fine Feed Depth (K value): the width and depth of fine cut.
• Step In Depth (Q value): the depth being machined per layer.
• If users enter values in both text boxes of Corner Rounding (R value) and Chamfering (L value), the later one will be ignored.
• Tilt Angle (D value): the angle which rectangular tool path tilted with.

• Spindle Feed Rate (I value): feed rate of spindle. Please refer to INCON-M84/M86/M86R Integration Manual for more information.
• Fine Feed Rate (E value): feed rate of fine cutting. If the value of Fine Feed Rate (E value) was left blank, system will replace the value with half of Feed Rate (F value) value.
• Feed Rate (F value): the velocity at which the cutter is fed, the system will adopt the value set last time if users do not make any changes.

• Users need to set the number of tool table (D_) and the tool radius before processing dowel machining.

Rectangular Dowel Machining